Tag Archives: Move_Body

Exploding a Multi-body part -2

Continued to my earlier post on exploding a multi body part, here is another example.  I have used a Weldment part for his example.

Example 2: Exploding a Weldment Part.

1. Click here to download the SW2011 part files used for this example.

2. Unzip and open up Weldment Part-2011 file.

3. Set the “3DSketch1″ to show. Right click or click on “3DSketch1″ and select show.

4. Also make sure sketches are set to show under View menu.

5. Go to Insert > Features and select Move/Copy Bodies

6. Select the two bodies as shown in the pic under bodies to move/copy.

7. Expand Translate (as we want to move out the body) and give 15mm as Delta Z value.

8. Click OK to close the close the command and apply the changes. The bodies have moved out by 15 mm in Z direction.

9. Restart Move/Copy Bodies command using step 5 or right click any where on the graphics area and select Recent Commands > Move/Copy Bodies. You’ll have to restart the command for further steps.

10. Select the side body as shown. Select the “3DSketch1″ line for direction and give -15 as the distance value.

11. Click OK to close the close the command and apply the changes. The body has moved out by 15 mm.

12. Select the two bodies as shown in the pic. Give -15mm as Delta X value.

13. Click OK to close the close the command and apply the changes. The bodies have moved out by 15 mm in X direction.

14. Select the side body as shown. Select the “3DSketch1″ line for direction and give -15 as the distance value.

15. Click OK to close the close the command and apply the changes. The body has moved out by 15 mm.

16. Select the two bodies as shown in the pic. Give -15mm as Delta Z value.

17. Click OK to close the close the command and apply the changes. The bodies have moved out by 15 mm in Z direction.

18. Select the side body as shown. Select the “3DSketch1″ line for direction and give 15 as the distance value.

19. Click OK to close the close the command and apply the changes. The body has moved out by 15 mm.

20. Select the two bodies as shown in the pic. Give 15mm as Delta X value.

21. Click OK to close the close the command and apply the changes. The bodies have moved out by 15 mm in X direction.

22. Select the side body as shown. Select the “3DSketch1″ line for direction and give 15 as the distance value.

23. Click OK to close the close the command and apply the changes. The body has moved out by 15 mm.

24. You may hide the “3DSketch1″ if required. Right click or click on “3DSketch1″ and select hide.

25. You may add two configurations one showing collapsed bodies where as other one showing exploded bodies.

26. Download the completed SW2011 part file here.

Exploding a Multi-body part -1

Many of us have been dealing with multi body parts and sometimes we need to show an exploded view similar to what we do in assembly to give a presentable picture of the parts or to show more details. Creating an exploded view in assembly is quite easy using the tool available. But are there any ways to replicate same in a multi body part.

Let’s explore the ways to do it:

Assembly Method: The easiest method is to convert the multi body part to assembly using this quick method : Assembly from Part – No mates required and then explode them using the exploded view tool.

Part Method:This particular method takes the advantage of move/copy bodies. Let’s discuss this method with some examples.

Example 1: Exploding a Multi Body Part.

1. Click here to download the SW2011 part file used for this example.

2. Unzip and open up Multi Body Part-2011 file.

3. Go to Insert > Features and select Move/Copy Bodies.

4. Select the “Side Plug” body (the blue colored) under bodies to move/copy.

5. Expand Translate (as we want to move out the body) and give40mm as Delta Z value. You may give direction or value for the move/copy if required for your parts.

6. Click OK to close the close the command and apply the changes. The “Side Plug” body has moved out by 40 mm in Z direction.

7. Restart Move/Copy Bodies command using step 3 or right click any where on the graphics area and select Recent Commands > Move/Copy Bodies.

8. Select the two “Round Plugs”.

9. Expand Translate and give 25mm as Delta Z value.

10. Click OK to close the close the command and apply the changes. The “Round Plugs” have moved out by 25 mm in Y direction.

11. You may add two configurations one showing collapsed bodies where as other showing exploded bodies.

12. Download the completed SW2011 part file here.

To be contd… Check Part 2 here